PHengLEI-TestCases/TwoD_30p30n_SST_Struct/bin/cfd_para_subsonic.hypara

#########################################################################
#                     General Control Parameter                         #
#########################################################################
// maxsimustep: the max simulation step, don't care simulation is restart or not.
// intervalStepFlow:       the step intervals for flow variables file 'flow.dat' saved.
// intervalStepPlot:   the step intervals for tecplot visual file 'tecflow.dat' saved.
// intervalStepForce:   the step intervals for aerodynamics coefficients file 'aircoef.dat' saved.
// intervalStepRes:    the step intervals for residual 'res.dat' saved.

int    maxSimuStep  = 50000;

int    intervalStepFlow        = 1000;
int    intervalStepPlot    = 1000;
int    intervalStepForce    = 100;
int    intervalStepRes    = 10;


// ifLowSpeedPrecon: precondition to accelerate convergence for low speed flow.
//         ONLY available for unstructured solver!
//              0 -- no precondition process (default, mach > 0.2). 
//              1 -- carry out precondition process ( mach number < 0.2 ).
int    ifLowSpeedPrecon        = 0;

#########################################################################
#                        		Inflow Parameter                        #
#########################################################################
// refMachNumber:             Mach number per meter.
// attackd:                           Angle of attack.
// angleSlide:                         Angle of sideslip.
// refReNumber:                          Reynolds number, which is based unit length, unit of 1/m.
// refDimensionalTemperature: dimensional reference temperature, or the total temperature only for the experiment condition.
// refDimensionalPressure:    dimensional reference pressure   , or the total pressure    only for the experiment condition.
// inflowParaType: the type of inflow parameters.
//                    0 - the nondimensional conditions.
//                    1 - the flight conditions.
// height:                            Fly height, unit of km.
// gridScaleFactor: The customizable unit of the grid, default value 1.0 metre.
// forceRefenenceLength, forceRefenenceArea:            Reference length and area, independent to grid scale.
// TorqueRefX, TorqueRefY, TorqueRefZ:   Reference point, independent to grid scale.

double refMachNumber    = 0.2;
double attackd                  = 19.0;
double angleSlide               = 0.00;

int    inflowParaType                       = 0;
double refReNumber                              = 9.0e6;
double refDimensionalTemperature    = 288.0;

//int    inflowParaType                     = 1;
//double height                             = 0.001;

double gridScaleFactor     = 1.0;

double forceRefenenceLengthSpanWise = 1.0;	// unit of meter.
double forceRefenenceLength   = 1.0;	// unit of meter.
double forceRefenenceArea     = 1.0;	// unit of meter^2
double TorqueRefX        = 0.0;	// unit of meter. 
double TorqueRefY        = 0.0;	// unit of meter.
double TorqueRefZ        = 0.0;	// unit of meter.

#*******************************************************************
#			          Physical models   	                       *
#*******************************************************************
// iviscous:           Viscous model 
//                         0 - Euler 
//                         1 - Lamilar
//                         3 - 1eq turbulent
//                         4 - 2eq turbulent
// viscousName :           Laminar or tubulent model
//                         - "1eq-sa", when iviscous = 3
//                         - "2eq-kw-menter-sst", when iviscous = 4
// DESType :         Type of DES
//                        0 - RANS (default);
//                        1 - DES;
//                        2 - DDES;
//                        3 - IDDES;

//int    iviscous        = 0;
//string viscousName        = "Euler";

//int    iviscous          = 1;
//string viscousName          = "laminar";

//int    iviscous        = 3;
//string viscousName         = "1eq-sa";

int    viscousType       = 4;
string viscousName         = "2eq-kw-menter-sst";

int     DESType       = 0;

int roeEntropyFixMethod   = 2;
double roeEntropyScale   = 1.0;
#########################################################################
#                       Spatial Discretisation                          #
#########################################################################
#*******************************************************************
#			  			Struct Solver		                       *
#*******************************************************************
// str_limiter_name:   Limiter of struct grid
//                         - "3rdsmooth",  "smooth" 
//                         - "nolim" - no limiter

string str_limiter_name    = "smooth";

#*******************************************************************
#			  			UnStruct Solver                  		   *
#*******************************************************************
// uns_limiter_name:   Limiter of Unstruct grid
//                         - "vencat"
//                         - "1st", meaning accuracy of first-order.
//                         - "nolim", no limiter.
// venkatCoeff:        Coefficient of vencat limiter, when uns_limiter_name = 'vencat'
//					   The smaller the value, the more robust it is.

string uns_limiter_name  = "vencat";
double venkatCoeff        = 50.0;

#########################################################################
#                       Temporal Discretisation                         #
#########################################################################
// iunsteady:           Steady or unsteady.
//                          0 - steady
//                          1 - unsteay 
// CFLEnd:             The CFL number, [0.1, 100]
//						The bigger the value, the convergence faster but lower robustness.
// nLUSGSSweeps:              Number of Sub-iteration of LU-SGS.
//						    1  : is recommended for structured solver.
//						    1-3: is recommended for unstructured solver.

int    iunsteady     = 0;

double CFLEnd      = 10.0;

int    nLUSGSSweeps        = 1;

#########################################################################
#                       Multi-Grid parameters                           #
#########################################################################
// nMGLevel: 	   The number of Multi-Grid level
//  			= 1 : Single level.
//              > 1 : multi-level.
// flowInitStep:  Flow initialization step, 0~500 is suggested.
//				  Multi-Grid : Number of steps computing on coarse grid, during flow initialization.
//				  Single-Grid: Number of steps computing using first-order with vanleer, during flow initialization.
           
int nMGLevel           = 1;
int flowInitStep   = 100;


#########################################################################
#                           File In or Out                              #
#########################################################################
// gridfile:       The partitioned Grid file path, using relative path,
//				   which is relative to the working directory.
//		IMPORTANT WARNNING: the file index should be ignored,
// 		                    e.g. if the partitioned grid is rae2822_hybrid2d__4_0.fts,
//					   			 Please use 'rae2822_hybrid2d__4.fts' here!
// isPlotVolumeField:   If dump out the whole field results to tecplot or not, 0/1.
		
string gridfile           = "./grid/30p30n_str__4.fts";
int    isPlotVolumeField        = 0;


// ----------------  advanced Parameters, DO NOT care it -----------
// nVisualVariables:  number of variables want to be dumped for tecplot visualization.
// visualVariables :  variable types dumped, listed as following:
//                      -- density(0), u(1), v(2), w(3), pressure(4), temperature(5), mach(6)
//                      -- viscosityLaminar(7), viscosityTurbulent(8)
//                      -- vorticity_x(9), vorticity_y(10), vorticity_z(11), vorticityMagnitude(12), strain_rate(13), Q_criteria(14)
//                      -- Cp(15), timeStep(16), volume(17)
//                      -- modeledTKE(18),modeleddissipationrate(19), SSTF1(20), SSTF2(21) 
// Important Warning: Array size of visualVariables MUST be equal to nVisualVariables!!!.
// Arriables order must from small to larger.
int    nVisualVariables     = 8;
int    visualVariables[]  = [0, 1, 2, 3, 4, 5, 6, 15];

// limitVariables:         limit model.
//                         0 - limit only for pressure and denstiny, then get the min value
//                         1 - limit for every variables, then get the min value
// limitVector:         
//			   			   0 - Each variable use the same limiter coefficient.
//                         1 - Each variable use the respective limiter coefficients.
// reconmeth:
//                         0 - When reconstruct face value, Q+, Q- use respective limiter coefficients.
//                         1 - Q+, Q- use the min limiter coefficients of left and right cell.
int reconmeth            = 1;
int limitVariables           = 0;
int limitVector          = 0;